Search the documentation
Enter at least 2 characters
 |
CAE Fidesys 9.0 Documentation |
Enter at least 2 characters
|
CAE Fidesys 9.0 Documentation |
1. Create a brick with a side of 1.3 mm.
On the command bar, select the module for constructing volume geometry (Mode - Geometry, Entity - Volume, Action - Create).
From the list of geometric primitives, select Brick.
Set the following parameters:
X (width): 1.3.
Click Apply.
2. Cut the volume.
On the command bar, select the module for constructing volume geometry (Mode - Geometry, Entity - Volume, Action - Webcut).
Select from the list Coordinate Plane.
Volume ID(s): 1;
Coordinate plane: XY;
Offset Value: -0.15;
Imprint;
Merge.
Click Apply.
3. Make a second incision.
On the command bar, select the module for constructing volume geometry (Mode - Geometry, Entity - Volume, Action - Webcut).
Select from the list Coordinate Plane.
Volume ID(s): 1;
Coordinate plane: XY;
Offset Value: 0.15;
Imprint;
Merge.
Click Apply.
On the command bar, select the volume mesh module (Mode — Mesh, Entity - Volume, Action - Intervals).
Set the following parameters:
Approximate Size;
Select Volumes: All;
Approximate Size: 0.05.
Click Apply Size.
Click Mesh.
In the command bar, select the module for specifying material properties (Mode - Material, Entity - Materials Management).
Create two materials.
Steel:
Young's modulus E = 2e+11;
Poisson ratio v = 0.25.
Rubber:
Young's modulus E = 2e+6;
Poisson ratio v = 0.49.
Click Apply.
Close the Materials management window.
1. Create a block of the same type of material.
On the command bar, select the block management module (Mode- Blocks, Entity - Block, Action – Add).
Set the following parameters:
Block ID: 1;
Entity List: Volume;
Entity ID(s): 3;
Click Apply.
2. Create a second block.
On the command bar, select the block management module (Mode- Blocks, Entity - Block, Action – Add).
Set the following parameters:
Block ID: 2;
Entity List: Volume;
Entity ID(s): 1 2;
Click Apply.
3. Set the parameters for block №1.
On the command bar, select the block management module (Mode- Blocks, Entity - Block, Action - Block properties/parameters).
Set the following parameters:
Block ID(s): 1;
Category: Solid;
Material: Steel;
Coordinate System: Global Cartesian;
Order: 1.
Click Apply.
4. Set the parameters for block №2.
On the command bar, select the block management module (Mode — Blocks, Entity - Block, Action - Block properties/parameters).
Set the following parameters:
Block ID(s): 2;
Category: Solid;
Material: Rubber;
Coordinate System: Global Cartesian;
Order: 1.
Click Apply.
1. Specify the type of task that you want to solve.
On the command bar, select the calculation settings module (Mode - Calculation Settings, Calculation settings — Effective Properties, Effective Properties- General).
Select:
Dimension: 3D;
Type of BC: Periodic;
Model: Elasticity.
Click Apply.
2. Set the solver settings.
On the command bar, select the calculation settings module (Mode - Calculation Settings, Calculation settings — Effective Properties, Effective Properties - Solver).
Select:
Method: Direct;
Use Uzawa iteration: Auto.
Click Apply.
Click Start Calculation.
In the window that appears, select:
Type of elastic properties: Orthotropic;
Type of temperature properties: Orthotropic.
Click Process the data.
The resulting orthotropic material will be automatically added to the list of materials.
Geometry creating, meshing, setting boundary conditions and materials can be performed using the console interface. Below is a link to the program code that allows you to perform the steps described above manual, you only need to specify the full path and name.